Toolpath Patterns

Introduction

Toolpath Patterning is used to create patterns of machining operations by copying one or more existing operations to other locations. You can create one or more Toolpath Patterns for a specific feature, or for all features contained in a Machine Setup, Index System, or Wrapping Group. There are three ways to create patterns. You can copy a feature at defined intervals using the Array option. The Translate option is used to copy and move features using the Delta method or the Sketch/Enter method. The third option, Rotate, is used to copy features at a defined angle interval (2D or 3D). Toolpath Patterns are supported for both Mill and Wire EDM.

To create a Toolpath Pattern, do one of the following:

To Pattern a single feature: in the CAM Tree, right-click the CAM feature name (such as Feature 3 Axis or Feature EDM 2X Inside), and click Add Toolpath Pattern.

To Pattern all features in a Machine Setup, right-click Machine Setup, point to Additional Functions, and click Add Toolpath Pattern. (For Wire EDM, right-click Machine Setup, and click Add Toolpath Pattern.)

To Pattern all features in a Index System, right-click Index System, point to Additional Functions, and click Add Toolpath Pattern. (Mill only)

To Pattern all features in a Wrapping Group, right-click Wrapping Group, point to Additional Functions, and click Add Toolpath Pattern. (Mill only)

When you add a pattern, a Toolpath Pattern item is added to the CAM Tree.

Machine Setup

Toolpath Pattern

Index System

Toolpath Pattern

CAM Feature

Toolpath Pattern

You can create one or more Toolpath Patterns for any feature, machine setup, index system, or wrapping group.

To compute a Toolpath Pattern:

When you add a toolpath pattern, the Toolpath Pattern dialog box displays.

After defining the pattern parameters, click OK.

The pattern is automatically calculated.

Toolpath Pattern Shortcut Menu

You right-click the Toolpath Pattern in the CAM Tree to access the following options.

Toolpath Pattern

Insert Toolpath Pattern - adds a new toolpath pattern below the selected pattern.
Edit - opens the Toolpath Pattern dialog box for you to modify the parameters for the selected pattern.
Delete - removes the selected Toolpath Pattern from the CAM Tree.
Post Yes/No - toggles whether or not the toolpath pattern is included in the posted NC program. When a pattern is set to not post, the icon is displayed.
Blank/Unblank Toolpath Pattern - is used to hide or show the computed Toolpath Pattern. When the pattern is hidden, the icon is displayed.

The Toolpath Pattern Dialog Box

When you add a toolpath pattern in the CAM Tree, the Toolpath Pattern dialog box is displayed. You must first select the method to define how the pattern is created.

Feature

Array - creates the pattern with a defined distance interval and number of copies along the X- and/or Y-axis direction.
Translate - creates a pattern with a defined number of copies using either the Delta or Sketch/Enter method.
Rotate - creates a pattern with a defined angle interval and number of copies rotated around a user-defined point or line (3D).
Point - creates a custom pattern, by allowing you to select a start point and various endpoints to place the copies in X, Y, and Z space.

The next section explains the dialog box parameters for each of the three methods separately.

Important: When defining values for toolpath patterns, for example when defining the point or line of rotation for the Rotate option, the values are based off of the machining origin that is defined in the Machine Setup dialog box and not the WCS (CAD world coordinate system).

Array

X Direction

Distance - the distance between each toolpath copy along the X-axis (direction).
Copies - the number of times the toolpath is copied.

Y Direction

Distance - the distance between each toolpath copy along the Y-axis (direction).
Copies - the number of times the toolpath is copied.

Translate

Delta - moves the toolpath by an incremental value from the current location.
Sketch/Enter - defines the pattern location either by selecting geometry or by typing coordinate values in the Start and End group. When using Pick to select geometry, the pattern is moved by the same distance and direction that is defined by the selected points.

Copies - the number of times the toolpath is copied.

Delta

When using the Delta method, type coordinate values to define the change in position, along each axis, from the current location.

X - is the distance of change from the current X-axis location.
Y - is the distance of change from the current Y-axis location.
Z - is the distance of change from the current Z-axis location.

Start

The Start and End groups define the start and end position when using the Sketch/Enter method. To define the Start point, you can type coordinate values, or use the Pick method.

X - is the X-axis location of the start point.
Y - is the Y-axis location of the start point.
Z - is the Z-axis location of the start point.
Pick - enables selection mode for you to select geometry from the graphics area to define the Starting location. The nearest snap point of the selected entity is used.

End

To define the End point, you can type coordinate values, or use the Pick method. The parameters are the same as explained in the Start group, except applied to the End point.

Rotate

3D Option (Mill only)

Select the check box to enable the Start and End groups for the Rotation Axis. Use this method when defining a line around which the pattern is rotated.

Clear the check box to enable the Origin group for the Rotation Axis. Use this method when defining a point (in X and Y) around which the pattern is rotated.

Angle - is the angle interval at which the toolpath pattern is created around a point (or a line when using the 3D Option). The angle is in reference to the positive X-axis (of the machining origin defined in the Machine Setup) when using a point. When using the 3D Option, the angle is in reference to the line defined by the Start and End parameters.
Copies - the number of times the toolpath is copied.

Rotation Axis

The options available in the Rotation Axis group change depending on whether or not the 3D option is selected. These options are explained next.

Origin

This groupis displayed when the 3D Option check box is cleared (turned off). The origin defines the point of rotation. You can type coordinate values, or you can use the Pick method.

X - is the X-axis location of the point of rotation.
Y - is the Y-axis location of the point of rotation.
Pick - enables selection mode for you to select the point of rotation from geometry in the graphics area.

Start

The Start and End group are displayed when the 3D Option check box is selected (turned on). You can type coordinate values, or use the Pick method to define the start point of the line used to rotate the pattern.

X - is the X-axis location of the start point.
Y - is the Y-axis location of the start point.
Z - is the Z-axis location of the start point.
Pick - enables selection mode for you to select the start point, of the rotation line, from geometry in the graphics area.

End

The End group defines the end point of the rotation line using the same parameters as the Start group, except applied to the end point.

Important: When creating toolpath patterns using the 3D Rotate option, the toolpath pattern is not applied to any features that are contained in a Wrapping Group.

Points

Specified Points

Start

The Start group defines the start position of the toolpaths to be patterned. To define the Start point, you can type coordinate values, or use the Pick method.

X - is the absolute X-axis location of the start point in reference to the machine setup.
Y - is the absolute Y-axis location of the start point in reference to the machine setup.
Z - is the absolute Z-axis location of the start point in reference to the machine setup.
Pick- enables selection mode for you to select geometry from the graphics area to define the start position with vertices, sketches and sketch points.

Positions

The Positions group defines the end positions of the toolpaths to be patterned. To define the Positions, you can use the Pick method, or type in coordinate values to add manually.

Pick

Pick Positions - enables selection modefor you to select geometry from the graphics area to define the end positions with vertices, sketches and sketch points.

Enter

X - is the absolute X-axis location of the end point in reference to the machine setup.
Y - is the absolute Y-axis location of the end point in reference to the machine setup.
Z - is the absolute Z-axis location of the end point in reference to the machine setup.
Add - Selecting the Add option will create a Position using the coordinates currently entered into the X,Y,Z dialogs. The new Position will be added to the list of Positions.
(Move Up) - moves the selected Position up one level.
(Move Down) - moves the selected Position down one level.
(Delete) - removes the selected Position from the list.

Machining Order

Optimized - the tool movement is reduced in the NC program.
Pick Order - outputs the positions in the NC program in the order they were selected for the pattern.

Toolpath to be patterned	Start Point


Positions	Result

Toolpath Patterns

Introduction

Navigation

Toolpath Pattern Shortcut Menu

The Toolpath Pattern Dialog Box

Array

Translate

Rotate

Points

Related Topics